HEIDENHAIN iTNC 530 Tap Cycle Help Conversational Format


Hi,
Will someone post or email some programming example of a tap cycle.
Specifically CYCL DEF 209 TAPPING W/ CHIP BRKG but 207 or 206
floating would be a big help.
I don't get an alarm, but I also don't get an tapped hole. Spindle
comes down to xy then z point then the spindle looks like it releases
from being engaged -it does a 1-degree wiggle- then home and done.
Sans guzinta.
CNC and control do have tapping. With no alarms popping up, it must
be me and it must be simple because i am simple.
Regards
Reply to
billynevada
Loading thread data ...
We do have a Heidenhain 426 at work, but not equipped with tap capabilities, so I'm told. I have only just begun figuring out Heid'ies programing language & machine tool functions. I do have manuals if they are similar to your 530 control? Would appreciate if you figure it out, to post the code showing that. Thx
====================================================== ______ /_____/\ Best Regards, /____ \\ \ Gil /_____\ \\ / HOLDZEM©® /_____/ \/ / / Made in USA /_____/ / \//\ By an \_____\//\ / / American Toolmaker \_____/ / /\ / West Chicago, IL \_____/ \\ \ USA \_____\ \\ \_____\/ ======================================================
Reply to
cncmillgil
I've been working on 530 for last two and a half years and 420 before that. I'm at home so if you can post or email me a blank code I will fill it in for you. Jerry
Reply to
Jerry
Jerry, sounds like your the Heidi guy? If you have second, could you post the code to sweep a like a 1"rad across X using Y-Z with say a 1/4"ball EM?- Any example will do, can't be that hard. I'm close. I've put in the example in the book, but it does not seem to be working properly with my dim's input. I'm a newbee to Heidi's conversational. Aint like no other I've run across. Kinda funuc macro/type hybrid- in a "league of its own". Actually really nice. They were way ahead of there time, considering its a mid 90's setup. I think it can blow away Hurco at certian things? If I can figure out how to hook the laptop up to it, one of these days, I'll pull out some of the prog's to play with. The other opition I have with this beast, is using ISO. Any experience with that? Any help would be appreciated. FYI this machine was never really used to its full capabilities, by what I'm seeing. Only been at this place for 8mo now - still learning
Reply to
cncmillgil
I will try to make that program tomorrow if I have few minutes. I don't program in ISO as Heidenhain is way nicer. Jerry
Jerry, sounds like your the Heidi guy? If you have second, could you post the code to sweep a like a 1"rad across X using Y-Z with say a 1/4"ball EM?- Any example will do, can't be that hard. I'm close. I've put in the example in the book, but it does not seem to be working properly with my dim's input. I'm a newbee to Heidi's conversational. Aint like no other I've run across. Kinda funuc macro/type hybrid- in a "league of its own". Actually really nice. They were way ahead of there time, considering its a mid 90's setup. I think it can blow away Hurco at certian things? If I can figure out how to hook the laptop up to it, one of these days, I'll pull out some of the prog's to play with. The other opition I have with this beast, is using ISO. Any experience with that? Any help would be appreciated. FYI this machine was never really used to its full capabilities, by what I'm seeing. Only been at this place for 8mo now - still learning
Reply to
Jerry
This is a simple program to tap 1/2-13 hole with two different cycles. Your machine zero may be different. Jerry
0 BEGIN PGM tap INCH 1 * - 1/2-13 tap, M3 not needed because spindle has to stop anyway to orient 2 * - examples of 2 taping cycles 3 BLK FORM 0.1 Z X-5 Y-5 Z-2 4 BLK FORM 0.2 X+5 Y+5 Z+0 5 TOOL CALL 1 Z S1000 6 CYCL DEF 247 DATUM SETTING ~ Q339=+1 ;DATUM NUMBER 7 L X+0 Y+0 R0 FMAX 8 L Z+0.2 R0 FMAX M8 9 CYCL DEF 207 RIGID TAPPING NEW ~ Q200=+0.2 ;SET-UP CLEARANCE ~ Q201=-0.7 ;DEPTH OF THREAD ~ Q239=+0.07692 ;THREAD PITCH ~ Q203=+0 ;SURFACE COORDINATE ~ Q204=+0.2 ;2ND SET-UP CLEARANCE 10 CYCL DEF 209 TAPPING W/ CHIP BRKG ~ Q200=+0.2 ;SET-UP CLEARANCE ~ Q201=-0.7 ;DEPTH OF THREAD ~ Q239=+0.07692 ;THREAD PITCH ~ Q203=+0 ;SURFACE COORDINATE ~ Q204=+0.2 ;2ND SET-UP CLEARANCE ~ Q257=+0.35 ;DEPTH FOR CHIP BRKNG ~ Q256=+0.03 ;DIST FOR CHIP BRKNG ~ Q336=+0 ;ANGLE OF SPINDLE 11 CYCL CALL 12 L Z+5 R0 FMAX M9 M5 13 L Z-0.1 Y-0.1 R0 FMAX M91 14 M30 15 END PGM tap INCH
Reply to
Jerry
Jerry, Thx. The guys in the shop I'm at say that they could never get the machine to tap. Saying it has to be equipped from the mfg. for taping? & also use a floating tap holder? Both are also mentioned in the manual. Hell I've never seen a CNC that could not G84 tap?, with or without a nice ext./comp.-slip clutch tap holder. Well I'm learn'in sumpin new???? Like I stated previously Heidi's way is different. We don't do alot of taping, plus we work with Titanium- real bear to tap. IMO Its not worth the chance on breaking a tap on, because usually 1 or 2 pcs in the order. TI is $$$ & so is EDM tap removal. My main concern is, an easy way to sweep simple Y/Z or X/Z contours across the block. The prog. manual has examples, but me not being familiar with all the commands, like CT CC ect. makes it confusing to apply to my work. Shit today I just figured out repeat label with an incremental Z (IZ) - the old loop tape method., only the repeat command counts how deep to go the the incremantal Z. Sweet! sit back,relax & let the machine do the work. This thing is like play time for me. Being on a weirdo ANAYAK & no toolchanger! I took a 3"wide 5mm dp. cut in TI the other day, the whole machine osilated & howled! Never hear nothing like that before. Nothing happend to the carbides on the face mill (positive 3/4"round inserts), it was just as it entered on the part. After it was in the cut no probelem. Sure did turn some heads. hehehehe. It has to be the way the machine tool is designed. The Y travels the Z column with it, not like most bed type mills where the Z is stationary & X/Y travel on the bed. Must have been like the way covers, kinda tiny tattle sound?? thanks again for your help. If time permits & the opertunity comes up, I would like to try your taping prog., even if its just to cut some air :-)
Reply to
cncmillgil
I have never seen a CNC machine that could not tap. You may not be able to rigid tap but with a floating holder you should have no problem. As for CC it means circle center and you need it for C (circular) and CP ( circular polar). CR only needs end position of circle and radius. The biggest fun on this control is to use variables (Qs). You can use it for simple stuff like changing depth of cut , cutter compensation and such but if you get really good with it you can actually use it for quite complex surfacing. Is your control 426 or 530? Jerry
Jerry, Thx. The guys in the shop I'm at say that they could never get the machine to tap. Saying it has to be equipped from the mfg. for taping? & also use a floating tap holder? Both are also mentioned in the manual. Hell I've never seen a CNC that could not G84 tap?, with or without a nice ext./comp.-slip clutch tap holder. Well I'm learn'in sumpin new???? Like I stated previously Heidi's way is different. We don't do alot of taping, plus we work with Titanium- real bear to tap. IMO Its not worth the chance on breaking a tap on, because usually 1 or 2 pcs in the order. TI is $$$ & so is EDM tap removal. My main concern is, an easy way to sweep simple Y/Z or X/Z contours across the block. The prog. manual has examples, but me not being familiar with all the commands, like CT CC ect. makes it confusing to apply to my work. Shit today I just figured out repeat label with an incremental Z (IZ) - the old loop tape method., only the repeat command counts how deep to go the the incremantal Z. Sweet! sit back,relax & let the machine do the work. This thing is like play time for me. Being on a weirdo ANAYAK & no toolchanger! I took a 3"wide 5mm dp. cut in TI the other day, the whole machine osilated & howled! Never hear nothing like that before. Nothing happend to the carbides on the face mill (positive 3/4"round inserts), it was just as it entered on the part. After it was in the cut no probelem. Sure did turn some heads. hehehehe. It has to be the way the machine tool is designed. The Y travels the Z column with it, not like most bed type mills where the Z is stationary & X/Y travel on the bed. Must have been like the way covers, kinda tiny tattle sound?? thanks again for your help. If time permits & the opertunity comes up, I would like to try your taping prog., even if its just to cut some air :-)
Reply to
Jerry
.
Ya your right CNC's all tap - I've put 1/2 * 3/8 taps in drill chucks & taped. After a few holes the tap pushes up(always), just feed hold, rejust & go!
Heidi's converational looks very powerfull for easy 3D shapes. It's just nobody ever dove in to it to make it work to its full extents previously at my place. Plus the boss like's Hurco's & so do I. Too bad, not much effort is going to be spent on the ol Heidi/Anayak. The table is huge, they could realy use a 4axis with a center/tailstock to cut round pcs to rectangle on the ends. Could even be a cheaper 4pos indexer? & the head swivels & looks like the control can be reset on that plane angle for axis travels? They are looking down the road of CNC lathe with live tooling.
Reply to
cncmillgil
Below are two simplest examples to do rad. One milling in X and other milling along the rad. Jerry
0 BEGIN PGM rad1 INCH 1 BLK FORM 0.1 Z X+0 Y+0 Z-2 2 BLK FORM 0.2 X+3 Y+3 Z+0 3 TOOL CALL 18 Z S5000 4 * - 0.25" ballnose 5 * - 0.5" rad 6 * - machining along X axis 7 CYCL DEF 247 DATUM SETTING ~ Q339=+0 ;DATUM NUMBER 8 L X-0.2 Y-0.125 R0 FMAX M3 9 L Z+0 R0 FMAX M8 10 CC Y+0.5 Z-0.625 11 L Z-0.625 R0 F500 12 LBL 1 13 LP IPA-5 R0 14 L X+3.2 15 LP IPA-5 16 L X-0.2 17 LBL 0 18 CALL LBL 1 REP8 19 L Z+6 R0 FMAX M9 M5 20 L Z-0.1 Y-0.1 R0 FMAX M91 21 M30 22 END PGM rad1 INCH
0 BEGIN PGM rad2 INCH 1 BLK FORM 0.1 Z X+0 Y+0 Z-2 2 BLK FORM 0.2 X+3 Y+3 Z+0 3 TOOL CALL 18 Z S5000 4 *
- 0.25" ballnose 5 * - 0.5" rad 6 * - machining along radius 7 CYCL DEF 247 DATUM SETTING ~ Q339=+0 ;DATUM NUMBER 8 L X-0.2 Y-0.125 R0 FMAX M3 9 L Z+0 R0 FMAX M8 10 CC Y+0.5 Z-0.625 11 L Z-0.625 R0 F500 12 LBL 1 13 L IX+0.01 14 CP IPA-90 DR- 15 L IX+0.01 16 CP IPA+90 DR+ 17 LBL 0 18 CALL LBL 1 REP160 19 L Z+6 R0 FMAX M9 M5 20 L Z-0.1 Y-0.1 R0 FMAX M91 21 M30 22 END PGM rad2 INCH
Jerry, sounds like your the Heidi guy? If you have second, could you post the code to sweep a like a 1"rad across X using Y-Z with say a 1/4"ball EM?- Any example will do, can't be that hard. I'm close. I've put in the example in the book, but it does not seem to be working properly with my dim's input. I'm a newbee to Heidi's conversational. Aint like no other I've run across. Kinda funuc macro/type hybrid- in a "league of its own". Actually really nice. They were way ahead of there time, considering its a mid 90's setup. I think it can blow away Hurco at certian things? If I can figure out how to hook the laptop up to it, one of these days, I'll pull out some of the prog's to play with. The other opition I have with this beast, is using ISO. Any experience with that? Any help would be appreciated. FYI this machine was never really used to its full capabilities, by what I'm seeing. Only been at this place for 8mo now - still learning
Reply to
Jerry
e:
rote:
Hmmmm......... its a gear drive head. max RPM 4K! hehehehe. But I'm not allowed to use that much. Aparentley the head heats up after??? & all the seals peuch oil. Oh boy..... kinda reminds of the ol Cincinnati Milcron 10v 2000 gear drive head. The first hour in the morning hydraulic oil seeped down to & thru the lower spindle outter bearings. We had a tin drip pan under the spindle for about 10min with it running to catch the drain oil. Run when first Turing on the spindle, else your very spotty after that. Well today was another learning experience on the beast. Heidi's way to mill a circle. WTH? Its just me. Not used to their "lingo" It aint G98/G99 fer rapid & travel planes- no damn R plane......... I'm lost. No G2/G3 its RL RL. Ah its just another language to add to all the rest of the cultural melting pots I've been in. DOS,UNIX,LINUX,WinBlows, Chinese,Polish,Laos,German,Russian,Swede, & of course See Habla press uono for gringo - dose for espanyol.
Hey anyone know about TIVO's? I wana hack into mine. Its an old Series 2 40hr record time. Works sweet! fer 20bucks at a garage sale. Their video play back/recording/FFwd/frame-frame is far superior my DishNetwork satellite DVR. By what I'm finding, its a Linux computer, programed to do what Tivo lets you to do. Not good enough for me. I want full control of the DVR/hard drive & file structure. I dont care about signing up for a tivo contract.
formatting link
Reply to
cncmillgil
Thanks for your posts. Norman at Bostomatic, too.
Here is a spot/drill/ rigid peck tap I got out of our CAM after some post tweaks. I am not versed in any Heidenhain programming so the structure may be off. Comments welcomed. But the trick was to get the post to issue hole locations after the cycle is defined. Then called with an M99 or a Location CYCLE CALL couplet.
Can the cycles all be defined then called later on in the program or must it be cycle/motion cycle/motion ?
And just in case you have concerns about running Internet servers out of drive space ..... I didn't want to edit the program for length lest I delete something which might lead to confusion.
; 0 BEGIN PGM 1 INCH ; FROM BEGIN PGM joe ; ;09/01/2009 08:08:08 AM ; C:\TAP THIS ; ; BLK FORM 0.1 Z X-1.0 Y-1.0 Z-1.1 BLK FORM 0.2 X+1.0 Y+1.0 Z+0.0110 ; ; CYCL DEF 247 DATUM SETTING~ Q339=3D+1; WORK SHIFT NUMBER ; ; CYCL DEF 32.0 TOLERANCE CYCL DEF 32.1 T0.001 CYCL DEF 32.2 HSC-MODE:0 TA0.01 ; ; ; TOOL NUMBER - 10 ; DESCRIPTION - CDRILL ; TOOL LENGTH FROM HOLDER 2.000 ; ; TOOL NUMBER - 11 ; DESCRIPTION - .070DIA ; TOOL LENGTH FROM HOLDER 3.500 ; ; TOOL NUMBER - 12 ; DESCRIPTION - 2-56 TAP ; TOOL LENGTH FROM HOLDER 2.000 ; 10 CYCL DEF 7.0 DATUM SHIFT 20 CYCL DEF 7.1 X+0 30 CYCL DEF 7.2 Y+0 40 CYCL DEF 7.3 Z+0 ; ;***CDRILL*** CYCL DEF 247 DATUM SETTING~ Q339=3D+1; WORK SHIFT NUMBER 50 TOOL CALL 10 Z S2000 ; ;***DRILL*** 60 L X.3835 Y.1625 R0 FMAX M3 70 L Z.05 FMAX 80 M8 90 L Z.05 FMAX 100 CYCL DEF 205 UNIVERSAL PECKING~ Q200=3D0.05 ;SET-UP CLEARANCE~ Q201=3D-0.055 ;DEPTH~ Q206=3D15 ;FEED RATE~ Q202=3D0.03 ;PLUNGE DEPTH~ Q203=3D0.0 ;SURFACE COORDINATE~ Q204=3D0.05 ;2ND SET-UP CLEARANCE~ Q212=3D0. ;DECREMENT~ Q205=3D0.0 ;MIN. PLUNGE DEPTH~ Q258=3D0.02 ;UPPER ADV STOP DIST~ Q259=3D0.04 ;LOWER ADV STOP DIST~ Q257=3D0 ;DEPTH FOR CHIP BREAKING~ Q256=3D0.02 ;DIST. FOR CHIP BREAKING~ Q211=3D1.0 ;DWELL AT DEPTH~ Q379=3D0 ;RETRACT FEED RATE~ Q253=3D0 ;DIST. FOR CHIP BREAKING 110 L X.3835 Y.1625 FMAX M3 120 CYCL CALL 130 L X1.0385 FMAX M99 140 L X1.6935 FMAX M99 150 L X2.3485 FMAX M99 160 L X3.0035 FMAX M99 170 L X3.6585 FMAX M99 180 L X4.3135 FMAX M99 190 L X4.9685 FMAX M99 200 L X4.3769 Y-.1625 FMAX M99 210 L X3.7219 FMAX M99 220 L X3.0669 FMAX M99 230 L X2.4119 FMAX M99 240 L X1.7569 FMAX M99 250 L X1.1019 FMAX M99 260 L X.4469 FMAX M99 270 L X-.2081 FMAX M99 280 L X.3835 Y-.3825 FMAX M99 290 L X1.0385 FMAX M99 300 L X1.6935 FMAX M99 310 L X2.3485 FMAX M99 320 L X3.0035 FMAX M99 330 L X3.6585 FMAX M99 340 L X4.3135 FMAX M99 350 L X4.9685 FMAX M99 360 L X4.3769 Y-.7075 FMAX M99 370 L X3.7219 FMAX M99 380 L X3.0669 FMAX M99 390 L X2.4119 FMAX M99 400 L X1.7569 FMAX M99 410 L X1.1019 FMAX M99 420 L X.4469 FMAX M99 430 L X-.2081 FMAX M99 440 L X.3835 Y-.9275 FMAX M99 450 L X1.0385 FMAX M99 460 L X1.6935 FMAX M99 470 L X2.3485 FMAX M99 480 L X3.0035 FMAX M99 490 L X3.6585 FMAX M99 500 L X4.3135 FMAX M99 510 L X4.9685 FMAX M99 520 L X4.3769 Y-1.2525 FMAX M99 530 L X3.7219 FMAX M99 540 L X3.0669 FMAX M99 550 L X2.4119 FMAX M99 560 L X1.7569 FMAX M99 570 L X1.1019 FMAX M99 580 L X.4469 FMAX M99 590 L X-.2081 FMAX M99 600 L X.3835 Y-1.4725 FMAX M99 610 L X1.0385 FMAX M99 620 L X1.6935 FMAX M99 630 L X2.3485 FMAX M99 640 L X3.0035 FMAX M99 650 L X3.6585 FMAX M99 660 L X4.3135 FMAX M99 670 L X4.9685 FMAX M99 680 L X4.3769 Y-1.7975 FMAX M99 690 L X3.7219 FMAX M99 700 L X3.0669 FMAX M99 710 L X2.4119 FMAX M99 720 L X1.7569 FMAX M99 730 L X1.1019 FMAX M99 740 L X.4469 FMAX M99 750 L X-.2081 FMAX M99 ; 760 M9 770 M5 M140 MB MAX 780 M1 ; PROGRAM STOP ; ; ;***.070DIA*** CYCL DEF 247 DATUM SETTING~ Q339=3D+1; WORK SHIFT NUMBER 790 TOOL CALL 11 Z S2000 ; ;***.070 DRILL*** 800 L X.3835 Y.1625 R0 FMAX M3 810 L Z.05 FMAX 820 M8 830 L Z.05 FMAX 840 CYCL DEF 205 UNIVERSAL PECKING~ Q200=3D0.05 ;SET-UP CLEARANCE~ Q201=3D-0.28 ;DEPTH~ Q206=3D13 ;FEED RATE~ Q202=3D0.06 ;PLUNGE DEPTH~ Q203=3D0.0 ;SURFACE COORDINATE~ Q204=3D0.05 ;2ND SET-UP CLEARANCE~ Q212=3D0. ;DECREMENT~ Q205=3D0.0 ;MIN. PLUNGE DEPTH~ Q258=3D0.02 ;UPPER ADV STOP DIST~ Q259=3D0.04 ;LOWER ADV STOP DIST~ Q257=3D0 ;DEPTH FOR CHIP BREAKING~ Q256=3D0.02 ;DIST. FOR CHIP BREAKING~ Q211=3D1.0 ;DWELL AT DEPTH~ Q379=3D0 ;RETRACT FEED RATE~ Q253=3D0 ;DIST. FOR CHIP BREAKING 850 L X.3835 Y.1625 FMAX M3 860 CYCL CALL 870 L X1.0385 FMAX M99 880 L X1.6935 FMAX M99 890 L X2.3485 FMAX M99 900 L X3.0035 FMAX M99 910 L X3.6585 FMAX M99 920 L X4.3135 FMAX M99 930 L X4.9685 FMAX M99 940 L X4.3769 Y-.1625 FMAX M99 950 L X3.7219 FMAX M99 960 L X3.0669 FMAX M99 970 L X2.4119 FMAX M99 980 L X1.7569 FMAX M99 990 L X1.1019 FMAX M99 1000 L X.4469 FMAX M99 1010 L X-.2081 FMAX M99 1020 L X.3835 Y-.3825 FMAX M99 1030 L X1.0385 FMAX M99 1040 L X1.6935 FMAX M99 1050 L X2.3485 FMAX M99 1060 L X3.0035 FMAX M99 1070 L X3.6585 FMAX M99 1080 L X4.3135 FMAX M99 1090 L X4.9685 FMAX M99 1100 L X4.3769 Y-.7075 FMAX M99 1110 L X3.7219 FMAX M99 1120 L X3.0669 FMAX M99 1130 L X2.4119 FMAX M99 1140 L X1.7569 FMAX M99 1150 L X1.1019 FMAX M99 1160 L X.4469 FMAX M99 1170 L X-.2081 FMAX M99 1180 L X.3835 Y-.9275 FMAX M99 1190 L X1.0385 FMAX M99 1200 L X1.6935 FMAX M99 1210 L X2.3485 FMAX M99 1220 L X3.0035 FMAX M99 1230 L X3.6585 FMAX M99 1240 L X4.3135 FMAX M99 1250 L X4.9685 FMAX M99 1260 L X4.3769 Y-1.2525 FMAX M99 1270 L X3.7219 FMAX M99 1280 L X3.0669 FMAX M99 1290 L X2.4119 FMAX M99 1300 L X1.7569 FMAX M99 1310 L X1.1019 FMAX M99 1320 L X.4469 FMAX M99 1330 L X-.2081 FMAX M99 1340 L X.3835 Y-1.4725 FMAX M99 1350 L X1.0385 FMAX M99 1360 L X1.6935 FMAX M99 1370 L X2.3485 FMAX M99 1380 L X3.0035 FMAX M99 1390 L X3.6585 FMAX M99 1400 L X4.3135 FMAX M99 1410 L X4.9685 FMAX M99 1420 L X4.3769 Y-1.7975 FMAX M99 1430 L X3.7219 FMAX M99 1440 L X3.0669 FMAX M99 1450 L X2.4119 FMAX M99 1460 L X1.7569 FMAX M99 1470 L X1.1019 FMAX M99 1480 L X.4469 FMAX M99 1490 L X-.2081 FMAX M99 ; 1500 M9 1510 M5 M140 MB MAX 1520 M1 ; PROGRAM STOP ; ; ;***2-56 TAP*** CYCL DEF 247 DATUM SETTING~ Q339=3D+1; WORK SHIFT NUMBER 1530 TOOL CALL 12 Z S600 ; ;***2-56 TAP*** 1540 L X.3835 Y.1625 R0 FMAX M3 1550 L Z.05 FMAX 1560 M8 1570 L FMAX 1580 L Z.05 FMAX 1590 CYCL DEF 209 TAPPING W/ CHIP BRKG ~ Q200=3D0.05 ;SET-UP CLEARANCE~ Q201=3D-0.265 ;DEPTH OF THREAD ~ Q239=3D0.0179 ;PITCH OF THREAD ~ Q203=3D0.0 ;SURFACE COORDINATE~ Q204=3D0.05 ;2ND SET-UP CLEARANCE~ Q257=3D0.085 ;DEPTH FOR CHIP BRKNG ~ Q256=3D0.02 ;DIST FOR CHIP BRKNG ~ Q336=3D0 ;ANGLE OF SPINDLE 1600 L X.3835 Y.1625 FMAX 1610 CYCL CALL 1620 L X1.0385 FMAX M99 1630 L X1.6935 FMAX M99 1640 L X2.3485 FMAX M99 1650 L X3.0035 FMAX M99 1660 L X3.6585 FMAX M99 1670 L X4.3135 FMAX M99 1680 L X4.9685 FMAX M99 1690 L X4.3769 Y-.1625 FMAX M99 1700 L X3.7219 FMAX M99 1710 L X3.0669 FMAX M99 1720 L X2.4119 FMAX M99 1730 L X1.7569 FMAX M99 1740 L X1.1019 FMAX M99 1750 L X.4469 FMAX M99 1760 L X-.2081 FMAX M99 1770 L X.3835 Y-.3825 FMAX M99 1780 L X1.0385 FMAX M99 1790 L X1.6935 FMAX M99 1800 L X2.3485 FMAX M99 1810 L X3.0035 FMAX M99 1820 L X3.6585 FMAX M99 1830 L X4.3135 FMAX M99 1840 L X4.9685 FMAX M99 1850 L X4.3769 Y-.7075 FMAX M99 1860 L X3.7219 FMAX M99 1870 L X3.0669 FMAX M99 1880 L X2.4119 FMAX M99 1890 L X1.7569 FMAX M99 1900 L X1.1019 FMAX M99 1910 L X.4469 FMAX M99 1920 L X-.2081 FMAX M99 1930 L X.3835 Y-.9275 FMAX M99 1940 L X1.0385 FMAX M99 1950 L X1.6935 FMAX M99 1960 L X2.3485 FMAX M99 1970 L X3.0035 FMAX M99 1980 L X3.6585 FMAX M99 1990 L X4.3135 FMAX M99 2000 L X4.9685 FMAX M99 2010 L X4.3769 Y-1.2525 FMAX M99 2020 L X3.7219 FMAX M99 2030 L X3.0669 FMAX M99 2040 L X2.4119 FMAX M99 2050 L X1.7569 FMAX M99 2060 L X1.1019 FMAX M99 2070 L X.4469 FMAX M99 2080 L X-.2081 FMAX M99 2090 L X.3835 Y-1.4725 FMAX M99 2100 L X1.0385 FMAX M99 2110 L X1.6935 FMAX M99 2120 L X2.3485 FMAX M99 2130 L X3.0035 FMAX M99 2140 L X3.6585 FMAX M99 2150 L X4.3135 FMAX M99 2160 L X4.9685 FMAX M99 2170 L X4.3769 Y-1.7975 FMAX M99 2180 L X3.7219 FMAX M99 2190 L X3.0669 FMAX M99 2200 L X2.4119 FMAX M99 2210 L X1.7569 FMAX M99 2220 L X1.1019 FMAX M99 2230 L X.4469 FMAX M99 2240 L X-.2081 FMAX M99 ; 2250 M9 2260 M5 ; M140 MB MAX CYCL DEF 247 DATUM SETTING~ Q339=3D+49; UNLOAD PART WORK SHIFT NUMBER L X0 Y0 FMAX CYCL DEF 247 DATUM SETTING~ Q339=3D+1; RELOAD ASS-U-MED WORK SHIFT NUMBER ; L R0 FMAX M30 END PGM 1 INCH
Reply to
billynevada
Every time you define a cycle like drilling or taping it takes precedence over any pervious cycle. If you are changing only one of the cycle parameters like say depth all you have to do is describe new Q value. For example you drill hole 1" deep (Q201=-0.055 ;DEPTH) before next hole you may describe Q201=-1.5 and next hole drilled with M99 will be 1.5" deep. Same with any other Q value in cycles. You could make a say LBL 10 with any cycle in it and call it up when needed. If you want to make your program smaller you can edit it like I did with your program below. All your positioning is in a label and is called up with every tool. Don't worry about the block numbers. When you send it to your machine it will rearrange it.
0 BEGIN PGM 1 INCH ; FROM BEGIN PGM joe BLK FORM 0.1 Z X-1.0 Y-1.0 Z-1.1 BLK FORM 0.2 X+1.0 Y+1.0 Z+0.0110 CYCL DEF 247 DATUM SETTING~ Q339=+1; WORK SHIFT NUMBER 10 CYCL DEF 7.0 DATUM SHIFT 20 CYCL DEF 7.1 X+0 30 CYCL DEF 7.2 Y+0 40 CYCL DEF 7.3 Z+0 CYCL DEF 247 DATUM SETTING~ Q339=+1; WORK SHIFT NUMBER 50 TOOL CALL 10 Z S2000; 55 TOOL NUMBER - 10 DESCRIPTION - CDRILL TOOL LENGTH FROM HOLDER 2.000 100 CYCL DEF 205 UNIVERSAL PECKING~ Q200=0.05 ;SET-UP CLEARANCE~ Q201=-0.055 ;DEPTH~ Q206=15 ;FEED RATE~ Q202=0.03 ;PLUNGE DEPTH~ Q203=0.0 ;SURFACE COORDINATE~ Q204=0.05 ;2ND SET-UP CLEARANCE~ Q212=0. ;DECREMENT~ Q205=0.0 ;MIN. PLUNGE DEPTH~ Q258=0.02 ;UPPER ADV STOP DIST~ Q259=0.04 ;LOWER ADV STOP DIST~ Q257=0 ;DEPTH FOR CHIP BREAKING~ Q256=0.02 ;DIST. FOR CHIP BREAKING~ Q211=1.0 ;DWELL AT DEPTH~ Q379=0 ;RETRACT FEED RATE~ Q253=0 ;DIST. FOR CHIP BREAKING 105 LBL 1 110 L X.3835 Y.1625 FMAX M3 120 CYCL CALL M8 130 L X1.0385 FMAX M99 140 L X1.6935 FMAX M99 150 L X2.3485 FMAX M99 160 L X3.0035 FMAX M99 170 L X3.6585 FMAX M99 180 L X4.3135 FMAX M99 190 L X4.9685 FMAX M99 200 L X4.3769 Y-.1625 FMAX M99 210 L X3.7219 FMAX M99 220 L X3.0669 FMAX M99 230 L X2.4119 FMAX M99 240 L X1.7569 FMAX M99 250 L X1.1019 FMAX M99 260 L X.4469 FMAX M99 270 L X-.2081 FMAX M99 280 L X.3835 Y-.3825 FMAX M99 290 L X1.0385 FMAX M99 300 L X1.6935 FMAX M99 310 L X2.3485 FMAX M99 320 L X3.0035 FMAX M99 330 L X3.6585 FMAX M99 340 L X4.3135 FMAX M99 350 L X4.9685 FMAX M99 360 L X4.3769 Y-.7075 FMAX M99 370 L X3.7219 FMAX M99 380 L X3.0669 FMAX M99 390 L X2.4119 FMAX M99 400 L X1.7569 FMAX M99 410 L X1.1019 FMAX M99 420 L X.4469 FMAX M99 430 L X-.2081 FMAX M99 440 L X.3835 Y-.9275 FMAX M99 450 L X1.0385 FMAX M99 460 L X1.6935 FMAX M99 470 L X2.3485 FMAX M99 480 L X3.0035 FMAX M99 490 L X3.6585 FMAX M99 500 L X4.3135 FMAX M99 510 L X4.9685 FMAX M99 520 L X4.3769 Y-1.2525 FMAX M99 530 L X3.7219 FMAX M99 540 L X3.0669 FMAX M99 550 L X2.4119 FMAX M99 560 L X1.7569 FMAX M99 570 L X1.1019 FMAX M99 580 L X.4469 FMAX M99 590 L X-.2081 FMAX M99 600 L X.3835 Y-1.4725 FMAX M99 610 L X1.0385 FMAX M99 620 L X1.6935 FMAX M99 630 L X2.3485 FMAX M99 640 L X3.0035 FMAX M99 650 L X3.6585 FMAX M99 660 L X4.3135 FMAX M99 670 L X4.9685 FMAX M99 680 L X4.3769 Y-1.7975 FMAX M99 690 L X3.7219 FMAX M99 700 L X3.0669 FMAX M99 710 L X2.4119 FMAX M99 720 L X1.7569 FMAX M99 730 L X1.1019 FMAX M99 740 L X.4469 FMAX M99 750 L X-.2081 FMAX M99 755 LBL 0 760 M9 770 M5 M140 MB MAX 780 M1 ; PROGRAM STOP 790 TOOL CALL 11 Z S2000 ; TOOL NUMBER - 11 DESCRIPTION - .070DIA TOOL LENGTH FROM HOLDER 3.500 840 CYCL DEF 205 UNIVERSAL PECKING~ Q200=0.05 ;SET-UP CLEARANCE~ Q201=-0.28 ;DEPTH~ Q206=13 ;FEED RATE~ Q202=0.06 ;PLUNGE DEPTH~ Q203=0.0 ;SURFACE COORDINATE~ Q204=0.05 ;2ND SET-UP CLEARANCE~ Q212=0. ;DECREMENT~ Q205=0.0 ;MIN. PLUNGE DEPTH~ Q258=0.02 ;UPPER ADV STOP DIST~ Q259=0.04 ;LOWER ADV STOP DIST~ Q257=0 ;DEPTH FOR CHIP BREAKING~ Q256=0.02 ;DIST. FOR CHIP BREAKING~ Q211=1.0 ;DWELL AT DEPTH~ Q379=0 ;RETRACT FEED RATE~ Q253=0 ;DIST. FOR CHIP BREAKING 1495 LBL CALL 1 1500 M9 1510 M5 M140 MB MAX 1520 M1 ; PROGRAM STOP CYCL DEF 247 DATUM SETTING~ Q339=+1; WORK SHIFT NUMBER 1530 TOOL CALL 12 Z S600 ; TOOL NUMBER - 12 DESCRIPTION - 2-56 TAP TOOL LENGTH FROM HOLDER 2.000 1590 CYCL DEF 209 TAPPING W/ CHIP BRKG ~ Q200=0.05 ;SET-UP CLEARANCE~ Q201=-0.265 ;DEPTH OF THREAD ~ Q239=0.0179 ;PITCH OF THREAD ~ Q203=0.0 ;SURFACE COORDINATE~ Q204=0.05 ;2ND SET-UP CLEARANCE~ Q257=0.085 ;DEPTH FOR CHIP BRKNG ~ Q256=0.02 ;DIST FOR CHIP BRKNG ~ Q336=0 ;ANGLE OF SPINDLE 1595 LBL CALL 1 2250 M9 2260 M5 M140 MB MAX CYCL DEF 247 DATUM SETTING~ Q339=+49; UNLOAD PART WORK SHIFT NUMBER L X0 Y0 FMAX CYCL DEF 247 DATUM SETTING~ Q339=+1; RELOAD ASS-U-MED WORK SHIFT NUMBER M30 END PGM 1 INCH
Thanks for your posts. Norman at Bostomatic, too.
Here is a spot/drill/ rigid peck tap I got out of our CAM after some post tweaks. I am not versed in any Heidenhain programming so the structure may be off. Comments welcomed. But the trick was to get the post to issue hole locations after the cycle is defined. Then called with an M99 or a Location CYCLE CALL couplet.
Can the cycles all be defined then called later on in the program or must it be cycle/motion cycle/motion ?
And just in case you have concerns about running Internet servers out of drive space ..... I didn't want to edit the program for length lest I delete something which might lead to confusion.
Reply to
Jerry
Thanks guys for the posts on Heidi's cycles. Looks like the 530 control has a lot more cycles than than the ol 426 I'm on.
Billynevada: What CAM system outputs Heidi format? I was thinking only ISO? Also guys, what machine tools is the control on?
Last Fri, I had a 24"sqr electrical cabinet the service guys wanted a "nice" 5" hole thru. What a fascicle. Setup top of the 2 kurts clapmed to wood. There was about 3/16-1/4" clearance to get the tool over & in. I thought I had more, but turns out the last little bit, maybe 1/2" of Z travel close to the upper limit switch is not usable during cycle. Only took an hour or so to figure that out. So after machine alignment, Z backs off the upper switch, so that position is max Z.
What's the cycle to just plunge & mill a circle- letting letting the slug fall? I only found pocketing(taking the middle out), but thats not what I wanted. Maybe there is no cycle, & its just input of circle cent & rad? Remember I have a vintage 1996 - 426. Hey that sounds like an old Hemi moter only 66-426?
Thanks for your help.
Reply to
cncmillgil
Hi cncmillgil. It is so easy to mill a circle like you describing there is no sense to use a cycle. All you do is to go to center of your pocket and down in Z and CC IX0 IY0 LP PR 2.5 PA 0 RL F ICP +360 DR+ Done. If you want to do this on 426 with a cycle you can lie to the control and add an even round number to you comp and the same to rad of your circle. This way cutter will go straight to the edge of your circle. We have Butlers, Correas and DMG with this control in our shop and if you programming on the machine and you are good you can program it faster than any other control I have ever seen. Jerry
Thanks guys for the posts on Heidi's cycles. Looks like the 530 control has a lot more cycles than than the ol 426 I'm on.
Billynevada: What CAM system outputs Heidi format? I was thinking only ISO? Also guys, what machine tools is the control on?
Last Fri, I had a 24"sqr electrical cabinet the service guys wanted a "nice" 5" hole thru. What a fascicle. Setup top of the 2 kurts clapmed to wood. There was about 3/16-1/4" clearance to get the tool over & in. I thought I had more, but turns out the last little bit, maybe 1/2" of Z travel close to the upper limit switch is not usable during cycle. Only took an hour or so to figure that out. So after machine alignment, Z backs off the upper switch, so that position is max Z.
What's the cycle to just plunge & mill a circle- letting letting the slug fall? I only found pocketing(taking the middle out), but thats not what I wanted. Maybe there is no cycle, & its just input of circle cent & rad? Remember I have a vintage 1996 - 426. Hey that sounds like an old Hemi moter only 66-426?
Thanks for your help.
Reply to
Jerry
.
I'm beginning to understand the format of Heide's language, finally! Got a lot of cycles down now,labels/repeats ect. Complex print geometry can be done with very little calulations. Heck, I'm a Hurco head, so for comparison, take away Hurco's DXF & I think Heide may be faster & smarter math wise. So, my standing question: How do I circular interpolate in Y-Z or X-Z? Being an ol ISO g-coder, Its G18/19 plane select, then I/J/K circ-cen. G2/G3- G91 increm. over- ect. How does that translate to Heide? Say I want to sweep a convex 1"R. across a 5"?(x or y) block using a 1/4"ball EM, taking .025" step overs? Sweeping simple 2.5D contours across blocks is a lot of what my place does. It aint rocket science, I was doing work like this back in '80, hand coding & manualy punching mylar tape, splicing the ends together to make a continuese running loop tape, by switching on block-delete / after prog is started, operator stops it after it runs off the block or before it cuts into the table.
Thanks Again. -- ___ ___ /
\ / /\ / /__\ / /\/\ /__/ / ------------------------------------ /__/\/\/ \ \ / ------------------------------------ \ \/\/ \ _\/ \__\/ Gil=A9
Reply to
cncmillgil
In one of my replays above I showed you how to put a rod on an edge. That sample is for a 0.5" rad but the principle is the same. There arte a lot of ways to do it but those are the two simplest.
0 BEGIN PGM rad1 INCH 1 BLK FORM 0.1 Z X+0 Y+0 Z-2 2 BLK FORM 0.2 X+3 Y+3 Z+0 3 TOOL CALL 18 Z S5000 4 * - 0.25" ballnose 5 * - 0.5" rad 6 * - machining along X axis 7 CYCL DEF 247 DATUM SETTING ~ Q339=+0 ;DATUM NUMBER 8 L X-0.2 Y-0.125 R0 FMAX M3 9 L Z+0 R0 FMAX M8 10 CC Y+0.5 Z-0.625 11 L Z-0.625 R0 F500 12 LBL 1 13 LP IPA-5 R0 14 L X+3.2 15 LP IPA-5 16 L X-0.2 17 LBL 0 18 CALL LBL 1 REP8 19 L Z+6 R0 FMAX M9 M5 20 L Z-0.1 Y-0.1 R0 FMAX M91 21 M30 22 END PGM rad1 INCH
0 BEGIN PGM rad2 INCH 1 BLK FORM 0.1 Z X+0 Y+0 Z-2 2 BLK FORM 0.2 X+3 Y+3 Z+0 3 TOOL CALL 18 Z S5000 4 *
- 0.25" ballnose 5 * - 0.5" rad 6 * - machining along radius 7 CYCL DEF 247 DATUM SETTING ~ Q339=+0 ;DATUM NUMBER 8 L X-0.2 Y-0.125 R0 FMAX M3 9 L Z+0 R0 FMAX M8 10 CC Y+0.5 Z-0.625 11 L Z-0.625 R0 F500 12 LBL 1 13 L IX+0.01 14 CP IPA-90 DR- 15 L IX+0.01 16 CP IPA+90 DR+ 17 LBL 0 18 CALL LBL 1 REP160 19 L Z+6 R0 FMAX M9 M5 20 L Z-0.1 Y-0.1 R0 FMAX M91 21 M30 22 END PGM rad2 INCH
erry
I'm beginning to understand the format of Heide's language, finally! Got a lot of cycles down now,labels/repeats ect. Complex print geometry can be done with very little calulations. Heck, I'm a Hurco head, so for comparison, take away Hurco's DXF & I think Heide may be faster & smarter math wise. So, my standing question: How do I circular interpolate in Y-Z or X-Z? Being an ol ISO g-coder, Its G18/19 plane select, then I/J/K circ-cen. G2/G3- G91 increm. over- ect. How does that translate to Heide? Say I want to sweep a convex 1"R. across a 5"?(x or y) block using a 1/4"ball EM, taking .025" step overs? Sweeping simple 2.5D contours across blocks is a lot of what my place does. It aint rocket science, I was doing work like this back in '80, hand coding & manualy punching mylar tape, splicing the ends together to make a continuese running loop tape, by switching on block-delete / after prog is started, operator stops it after it runs off the block or before it cuts into the table.
Thanks Again. -- ___ ___ /
\ / /\ / /__\ / /\/\ /__/ / ------------------------------------ /__/\/\/ \ \ / ------------------------------------ \ \/\/ \ _\/ \__\/ Gil©
Reply to
Jerry
.
...
Looks all "greek" to me:-) I will give these a try tomorrow during a long run on slots.
Thanks -- ___ ___ / \ / /\ / /__\ / /\/\ /__/ / ------------------------------------ /__/\/\/ \ \ / ------------------------------------ \ \/\/ \ _\/ \__\/ Gil=A9
Reply to
cncmillgil
.
...
om...
Help Mr. Wizzard Help! This F'in Ol Basdard 426 will be my bitch some day......... Ain no damn CNC freekin control gonna intimadate me I'm good at fegger'in out stuff ya no..........:-) Like back in 95, A Mitsubishi v55 with the M2a control. that was another sleeping giant. Slow as a turtle but a great moldbase machine.
formatting link
Reply to
cncmillgil
...
om...
.com...
Ok overall consensise so far, about 25-50hrs actual machine time over the last 9mo. Heidenhain 426 conversational input on Anayak VH1800. Its a bitch The thinking mentality , logic, behind the the predefined cycles are different than today. Gotta remember they did not have & readily avalaible, good CAM systems to get data feed to the machine & get'r running. Besides Mastercam/Smartcam/Sufcam early 90 ish. High end systems McD/Slumberje?/CV/Camax/IT/ were the few REAL cam systems out there, and were few & far between. So take a shop floor guy & give'em a way to get basic geometry off basic prints in to the machine, let the control do all the hard trig math, with a few "rules" for those cycles & wala! Yer cut'in 3D shit with cycle looping /inrementaly progressing & multi passing milling controled by number of repeats stuff. Plus while the machine is running, next up programs can be witten/ screen tested(backploted),pre difined work offsets calculated(programing in background). & it has its own user defined macro input called "Q" programs for "family of parts" type work. . Make a d It's input & editing key functions & terminolgy are kinda funky as comparied to US? IE: no entry=3Dclear entry - NC start=3DCycle Start NC stop=3Dinterrupt cycle/feed hold. It's ok, but just makes you think for a second. The reasoning is, that control was put on all kinds of machines, prolly robots & other cnc controled equipt. So across the board terminolgy is used. Its just another Freekin machine tool. Another notch in the belt. Gonna need a bigger belt here soon. As I said before, I will own you bitch! You are a piece of ancient shit. But you still work, so this crazy ol moldmaker is gonna have some fun with you, with your big ass 50taper (no tool changer) 30hp gear drive dick head shaped head. This machine tool is what happens when German engineering & Spanish engineering get together. WTH? were they thinking? Freekin goof balls. Such a big ass machine but not enough rigidity to hold large face mills from deflection - noticed on mainly exit off of part. Just slightly, again noticalble by cutter marks (trailing & leading edge) & size measurement. +-.001 over 4"dia face mill. Not so much head out of sqr as seen from stepover, but deflection in direction of travel. Its gotta be not enough strength by desgin of the physical head shape. It looks like a swivel dick sticking out of the Y carrage. This compact swiveling head design was intended for a purpose.? Maybe tall cores/ castings with small corner radii? Thus the head could be swiveled to gain access way down vertical walls? Its big enough & strong enough to preform very well at jobs like that. Kinda reminds me of giant version of the old Bridgeport "Quilmaster" head. With a huge X(70") Y Z travels open bed, full front loading - door access. You just don't see the likes of one of these too often. I dont think this beast has ever been fully tammed. This shop has been "captive" so production output was not much? Any hoot, its a play thing for me, as I feel semi-retired at 52. I just do this shit so I dont get bored, as can be clearly seen here, by me wasting my time here
Ya Ya you know, Its German..........the BEST! oh sorry Swiss,& Norwegian guys.
Reply to
cncmillgil

PolyTech Forum website is not affiliated with any of the manufacturers or service providers discussed here. All logos and trade names are the property of their respective owners.