Request for a flexible, flexible object (ehm...)

Hi everyone, I'm new to the newsgroup, did a quick search but could not find an answer to this question.
I've been using Pro/Engineer for a couple of years, mainly to do
optical devices packaging, but recently I got stuck with this problem, it's quite difficult to explain, I'll try to be as clear as possible.
Let's say I have a "tubular" object, a sort of pipe with a custom profile (imagine a string of fixed length with several pearls at fixed positions), and I want do deform it so that it starts from a given point and ends to another, tangent to two axis. I can use spinal bend with a sketched curve and it works fine, but it doesn't keep the spine length of the object intact, I.E. it adapt the object length to the length of the path. Is there a solution in Wildfire 2.0 for this problem?
I can also forget about the sketch and simply define a datum curve from point A to point B, but not fix its length, and that's the problem.
And then comes the second part of the problem: in an assembly I have many of this "strings", and they have to start and end all at different points. Is it possible to do it in some way? With flexible components maybe?
I hope someone can give an help
Paolo
Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload
everyone, I'm new to the newsgroup, did a quick search but could<BR>not find an answer to this question.<BR><BR>I've been using Pro/Engineer for a couple of years, mainly to do<BR>optical devices packaging, but recently I got stuck with this problem,<BR>it's quite difficult to explain, I'll try to be as clear as possible.<BR><BR>Let's say I have a "tubular" object, a sort of pipe with a custom<BR>profile (imagine a string of fixed length with several pearls at fixed<BR>positions), and I want do deform it so that it starts from a given<BR>point and ends to another, tangent to two axis. I can use spinal bend<BR>with a sketched curve and it works fine, but it doesn't keep the spine<BR>length of the object intact, I.E. it adapt the object length to the<BR>length of the path. Is there a solution in Wildfire 2.0 for this<BR>problem?<BR><BR>I can also forget about the sketch and simply define a datum curve<BR>from point A to point B, but not fix its length, and that's the<BR>problem.<BR><BR>And then comes the second part of the problem: in an assembly I have<BR>many of this "strings", and they have to start and end all at<BR>different points. Is it possible to do it in some way? With flexible<BR>components maybe?<BR><BR>I hope someone can give an help<BR><BR>Paolo<BR></BLOCKQUOTE> <DIV>This might work, but I haven't tried it: Create a spherical surface, create points on the surface (if references are needed, pick the csys and look for a csys type of spherical, though it probably doesn't matter.) Create datums through the points and tangent to the sphere. Create axes through the point and normal to the planes. Put another point at the center of the sphere. Create a 'through points' curve and pick outer, center and outer points. For tangency each end, pick the axes for start and end points. Only question is: will the length vary.</DIV> <DIV>&nbsp;</DIV> <DIV>Here's another one that's been recommended before: use sheet metal because it unbends naturally and retains its length. But, in your case, I'd suggest a variation, an additonal step. 'Wrap' a curve onto the sheetmetal and use this for your trajectory.</DIV> <DIV>&nbsp;</DIV> <DIV>David Janes</DIV></BODY></HTML>
------=
Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload

unbends naturally and retains its length. But, in your case, I'd suggest a variation, an additonal step. 'Wrap' a curve onto the sheetmetal and use this for your trajectory.
Thank you David, actually I never thought of using sheetmetal for this issue, I'll have to try it!
Paolo
Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload
Paolo, If you create the extrusion as a sweep and use insert datum curve thru points. Use a start and end point and then add points along the line as you need and use the tweek command to show the variation or the bending. Paolo Zago wrote:

it unbends naturally and retains its length. But, in your case, I'd suggest a variation, an additonal step. 'Wrap' a curve onto the sheetmetal and use this for your trajectory.

Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload

But the swept extrusion will have a "tube like" shape, I need something that has also a variable section, imagine for example the metallic or plastic tube of a shower that has a fixed length and fixed number of ribs, I'd like to be able to conform it to an entry and exit point.
Paolo
Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload
If you want to use flexibility, I would setup 3 flexible dimensions/ parameters: 2 for the position of the endpoint of the tube (you only need 2 because I'm guessing the bend line will always lie within a plane), 1 for the tangent angle at the endpoint. You can then create a sweep profile between your start and end points. I would create the path using 1 arc tangent to line segments. One line segment should be verical, and the other line sigment should be coincident with the endpoint and its orientation controlled via angle dimension relative to the first segment. If you dig a bit on the synthx.com website, you'll see that it's possible to dimension the length of an arc. After you create the arc length dimension, make it reference (non- driving). Now you at least have the means to measure the total path/ tube length and apply some relatively indepth relations to maintain a constant path length. It would be up to you to enter endpoint location and angle that are achievable for a given length tube. I'll leave the geometry/trig relations for you to figure out.
Regarding your qualms about using a sweep; if your custom cross- section can be described using equations, you can use a sketch relation inside a VSS (variable section sweep) instead of a normal sweep. For example, the equation below would yield a sinusoidally varying cross-section with N bulges and a max/min radius of (R0+A) and R0, respectively.
R = R0 + A*sin(N*360*trajpar)
Another option is to use a graph to custom plot your cross-sectional variation. Seems like a lot of work for such a simple task. I'd ask for funding to buy the routing package. I'm pretty sure it can handle things like finite length tubes.

Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload
Paolo, after you create the sweep (datum curve), just select the curve, hit the var section sweep icon and sketch all the sections you need. You can go back and redefine the datum curve to add or remove more points and tweek it where you need it.
Gary takedown wrote:

Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload

Thank you all, I really have some material to experiment now :) I'll let you know how things will evolve.
@ TC I don't think we can attach binaries, if I get to solve the problem (which is not highest priority for me too) I can send you the parts by email :)
Paolo
Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload
Paolo, If you menage to solve your problem, could you send that part to me. I have somethnig similar but it never became my top priority and it's still waiting to be solved...
Can we add attachmants to posts in this newsgroup?
Second part of your problem was that you have an assembly with many of those parts. It can be done with "make flexibile" command. Make those parts flexibile and define each one of them independently inside the assembly.

Add pictures here
<% if( /^image/.test(type) ){ %>
<% } %>
<%-name%>
Add image file
Upload

Polytechforum.com is a website by engineers for engineers. It is not affiliated with any of manufacturers or vendors discussed here. All logos and trade names are the property of their respective owners.