While you might get the code you want here I'd say if you want something done do
Grab your controller manual and search it up, you might learn other things from
it. If you dont have the manual search for a pdf.
BTW, I have no idea what the code might be.
This may be of assistance.....
Posted 21 March 2011 - 09:04 AM
I need to make a 6-32 Tap hole,but I don't know the code line(G
Posted 21 March 2011 - 10:15 AM
lathes are tricky
rigid tapping this may help.
M29 (may or may not need this)
G84 Z-.975 R0.1 F.03125 S600 M03 (Rigid tap Cycle)
G28 U0 W0.
Note per feed per rev feed is pitch of 6-32.
Posted 21 March 2011 - 03:12 PM
It's been a while but I think it's G32 on Fanuc lathes.
Posted 21 March 2011 - 06:01 PM
Yes G32/G33 is the ticket, you will not be able to rigid on a 10T,
you'll need to use a floating tap holder.
Some machines will alow you to M04 without M05ing.
so it's like
G97 M03 S200
G00 X0. Z.25
G32 Z-.5 F.03125
G32 Z.25 F.03125
G00 X10. Z 5.
Posted 23 March 2011 - 10:31 AM
I apologize for giving you bad information, those guys are right. I
was wrong and stand corrected. Didn't read what you had close
enough...My Bad :(
Posted 24 March 2011 - 03:00 PM
Thx Guys for help me,I figure out my program. it 's work fine.
NO.6-32 RH TAP)
N1020 G0 T0505
N1040 G97 S100 M03
N1050 G0 G54 X0. Z.25
N1070 G99 G1 Z-.255 F0.03125
N1090 G97 S100 M04
N1120 G97 S500 M03
N1130 G28 U0. W0.
N1140 G00 T0500
Posted 24 March 2011 - 06:40 PM
You'll want to change that G01 to a G32 because the feed override is
active on a G01 not a G32
The tapping codes for the OmniTurn are somewhat generic for many Fanuc
controls.....within the learning curve anyways.
Gunner, surprised to see his photo on the title page.
G32 will probably work.
Takes 2 blocks and you also need to pay close attention to spindle control
code m3 m4 m5 word placement or else ypur tap will break off if you run it
in single block mode.
1) feed tap to depth in the first block using correct feed/speed ratio and
g32 and make sure there's an m5 is at the end of this block
2) then in the next block, feed back out again using correct feed/speed
ratio and g32 but with an m4 placed at the start of this block.
Polytechforum.com is a website by engineers for engineers. It is not affiliated with any of manufacturers or vendors discussed here.
All logos and trade names are the property of their respective owners.