There are many ways to do this, which I'm sure the informative people
in this group will inform you about. However, if I wanted to make a
spiraling phone cord with arbitrary profile/trajectory I would do it in
1. Create the base trajectory that the cord will follow. This can be a
simple 2D spline or you can get creative by projecting a 2D sketch onto
an arbitrary curved surface.
2. Create a Variable Section Sweep (VSS) that uses the previous
trajectory to create a spiraling surface. The profile sketch will be a
simple line that starts at the trajectory center and extends out at an
angle. The lengh of this line will be the radius of the spirals in the
cord. Use relations to drive the line angle with the trajpar parameter.
sd1 = 45 + trajpar*360*10
Trajpar = 0 to 1 as the sweep progresses along its trajectory
10 = number of complete turns
360 degrees per complete turn
45 is there because ProE doesn't like starting at 0 degrees
3. Create another VSS that uses the edge of the surfaces created in the
last step as the trajectory. The profile sketch can be whatever you
want, but a simple circle centered on the trajectory should be fine.
Voila! You've got a phone cord. If your needs are simpler you could
make a straight spiraled cord using the Helical Sweep function. Also,
if you don't mind your cord not having a perfectly circular
cross-section, you could omit one of the VSS's (feature 2) and just
spiral a circular profile around the trajectory curve using trajpar and
relations. Hope this helps.