How to copy a Sketch

Well, have you tried the mighty Copy & Paste tools in the Edit menu?
-h-

Edit->Copy/Paste doesn't work for coping the whole plane with the sketch on it.

How about using a Derived Sketch?
'Sporky'

You have to make the plane first, then copy the sketch onto the new plane. I don't know of any way to do them both at once.
Jerry Steiger Tripod Data Systems "take the garbage out, dear"

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Cutting, Copying, and Pasting Sketch Entities You can cut and paste, or copy and paste, one or more sketch entities from one sketch to another or within the same sketch. Select the sketch entities and drag while using the following keys: · To copy within the same document or different documents, hold down the Ctrl key while dragging. · To move within the same sketch, hold down the Shift key while dragging. · To move between different documents, hold down the Ctrl key and drag the sketch entities into the second document. Then release the Ctrl key, hold down the Shift key, and drop the sketch. NOTE: A new sketch has to be open in the target document to drag a sketch into the document. Additionally, you can copy by selecting one or more sketch entities and clicking Edit, Copy, or by pressing Ctrl+C. Then you can paste the entities by clicking in the graphics area and clicking Edit, Paste or pressing Ctrl+V. The center of the sketch entities is placed at the point you clicked. Copying and Pasting Entire Sketches You can copy an entire sketch and paste it on a face in the current part, or you can paste it into a different sketch, or into a part, assembly, or drawing document. The target document must be open. To copy and paste a sketch: 1. Select the closed sketch in the FeatureManager design tree. 2. Click Edit, Copy, or press Ctrl+C. 3. Click in the sketch or document where you want to paste the center of the sketch. 4. Click Edit, Paste, or press Ctrl+V. NOTE: Copying a sketch does not copy the relations.

That's because there isn't a way to copy the plane and the sketch, only the sketch to a new plane.
Regards, Scott

Autocad has some slight problem using the windows copy and paste, unless you use the copy with basepoint command. There can be a very slight change in the items being copied. It has something to do with copy using Windows OLE, and copy with basepoint using Acad specific info.
I don't know if SW shares this problem. If not, then this is just trivia for those living in both software.
Peace

Alex,
I have to take exception to your statement "NOTE: Copying a sketch does not copy the relations."
Often it is vital to copy a sketch and maintain its relations and dimensions, if only to eliminate the need to apply the constraints again manually.
This can be done quite easily (however, any external dimensions or relations are excluded) by means of dragging and dropping or with Ctrl-C / Ctrl-V.
It is necessary to perform such copy operations with the sketch CLOSED, selected from the Feature Manager and pasted onto a face, plane or viewport background with NO sketch OPEN to receive the entities!. If the sketch entities are copied from or to an open edit window, then the constraints will be lost (although sometimes it's desirable to leave them behind)...
Per O. Hoel __________________________________________________
sketch in it.