surface copy

Hello,
I'm looking for several hours for copiing surfaces in WF2 (from an other
part or the same part).
With proE 2001, it was possible to do [Surface / new (create) / copy] and
then copy solid surface or composite surface.
Now the menu help translation tell me to do copy & paste but I can't copy
entire solid surface of an other (or the same) part for example.
Can someone could tell me where I can find help about this ?
Thanks,
GB
Reply to
g. bon
Loading thread data ...
Select the surface / quilt (not the feature), Edit, Copy Edit, Paste (or ctrl+c, ctrl+v)
Look at your start up browser. There are (I think?) links to a menu mapper and WF selection techniques tutorial.
Reply to
Jeff Howard
thanks, but I can't copy the whole volume of a part as it was possible with copy / solid surface.
I was speaking about the menu mapper when I said that they just say "copy and paste" but I can't do this with a whole solid part.
"Jeff Howard" a écrit dans le message de news: 4%DRf.3387$ snipped-for-privacy@newsread1.news.pas.earthlink.net...
Reply to
g. bon
Select a surface / quilt, rmb, Solid Surfs.
Reply to
Jeff Howard
Oops, sorry. Select a solid face, rmb, ....
(Never having used pre-WF, if I'm missing the issue someone please correct me.)
Reply to
Jeff Howard
I think most of this is a technical problem of selection with WF. When you get the initial pre-highlight it should be of some big solid protrusion. When you click on it and it turns red, all you need to do is move the cursor a little and a surface of the solid will prehighlight. Click select that and it should turn a mauvish color. Then, RMB 'Solid Surfaces' and you have all the external surfaces of the solid selected. Now do ^C/^V and you'll get your whole part surface copy. To prove it to yourself, while the copied surface is still highlighted, do 'Edit>Offset'. Pro/e will more than likely try to offset in the wrong direction and give you no preview geometry. Just hit the reverse arrow and you should see your copied surface offset the given amount.
Reply to
David Janes
You may have to go into Tools - Assembly Settings - Reference control - geometry and set 'all' and 'all' if you are copying geometry between models.
Reply to
John Wade

PolyTech Forum website is not affiliated with any of the manufacturers or service providers discussed here. All logos and trade names are the property of their respective owners.