finding reason for under defined

I am working in SW 06, in my sketch I have about 2/3 of my lines black
(defined). The other 1/3 are blue (underdefined). I cannot see where I
do not have a relation put in that it needs. Is there any tool that
will aide me in discovering where I need a relation to be put in to
fully define the sketch? I keep trying to add some dimensions, and am
getting over defined warnings.
Reply to
billyb
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To me, one of the best diagnostics available for determining what constraints need to be added to your sketch is just to simply click and drag on the various entities to see if any of them allow any movement. Don't be shy about clicking and dragging on the sketch entities--both the lines and the vertices. Once you've worked your way around all the entities in the sketch, it should become obvious what additional relationships are required. Sometimes, you may have a situation where all the lines are black but the sketch shows as underdefined--this can happen when there are vertices that are still underdefined. A very useful setting to help with this is under Tools, Options, System Options, Sketch. Make sure that you enable the "Display Entity Points in part/assembly sketches". This way, you'll see a dot at the end points of every entity. If you adopt the habit of dragging on your sketch entities, quickly, you'll get a more intuitive feel for what constraints need to be added in order to fully define the sketch.
Something to look forward to in SW2007 is the SketchXpert command, which provides some additional automation for fully defining a sketch.
If you're still having trouble with this particular sketch, I don't mind taking a look at it for you--feel free to email me the part file if you like.
Reply to
bwilliamson
What if you use the autodimension?
Reply to
Bruce Bretschneider
Good point. Autodimension will definitely work; however, it may not give you a dimension scheme that's consistent with your design intent.
Reply to
bwilliamson
In addition, I wonder if there is a method to make it easier to find the occassional darned little .001-.003" long bits that extend past an intersection with no visibility when zoomed out of any color or length?
I am sure that grabbing and dragging will work, but with 5-10 dozen objects in the inevitable sketch which causes the problem, that is still tough to find.
I have found one way with very complex sketches to be sure I don't get an undefined object that is tough to find when I just know some profile sketches are going to be a bitch.
In those cases, I dimension as I go along with each object or two or three, even if I know I must change the dimensions and relations later. This has advantages of letting me adjust the size of the relative positions of entities in the sketch as I go along, if it obviously requires a rethink or reposition of some element.
Bo
Reply to
Bo
quoted text -
I want to thank all of you for the great suggestions! I also discovered the diagnostic tools which I am also using.
Reply to
billyb

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