Assembly Sketch Relation problem...

Hi All. I am using most current version SW(2007 SP4). Here is my trouble:
I am designing a mold base. I need to add EJ holes to the EJ plate.
The inserts are all in place in the Assy, along with current EJ locations.
When I edit the part (in Assy window) I can use Convert entities to get my hole locations, but I cant get it to go Concentric with the Insert block. (it wont put the concentric relation in to the current EJ holes in the Insert blocks). I dont get it, this worked for me before. IF there a bug I dont know about??..
I need this to update the locations automatically if I change the insert blocks(Shrink may change).
Any input is appreciated
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In order to get good help, you have to be more careful about how you say things. I can't decipher what you're saying at all.
possibilities based on guesses:
- the things that you are trying to make something else concentric to aren't circular. concentric sketch relation or concentric mate? edge or face? I'll let you figure out how to figure out if something is circular or not
- if you have already converted a sketch entity, you don't need to make it concentric (unless you have the switch turned on that deletes the relations as soon as you make them)
- if you have created a part using a convert entity, you don't need to mate that part. That over defines everything.
- of course you're aware of the difference between an assembly sketch and a sketch in a part being edited in the context of an assembly
Daisy
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Yeah, Im trying to explain it so it makes sense,lol..here goes:
Simple holes here. I have an assembly with inserts in it. The inserts have holes. I need to project the holes down to another part (EJ Plate) in the assembly. I am editing the EJ plate in context in the asembly. I can use Derived sketches or can also use Convert entities.
The problem is, the sketch is not fully defined, I can drag it and move it out of position. I try to add a Concentric relation, in context to the holes in the upper part of the assy, and its a no go. It will snap to the center if dragged, but dont add the relation. I also cannot manuall add any relations either.

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Ok, I just talked with SW. I had the No external Refrences checkbox in the Assemblys Toolbar checked. Man thats so not obvious,lol... Sorry for the stupid question..;) thanks for the help..:)
CD

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Ok, there is a function on your Assembly toolbar called "No External Relations". This is probably pressed in, and you need to un-press it. It looks like a yellow upside down T block with a blue cube with a chain link with a red X. You can also get to this setting in Tools Options External References => Do not create references external to the model.
Daisy
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Just a tip from my experience. Don't convert entities in context in an assembly if you can help it. It can get confusing and is buggy. A better idea, IMHO, is to create a sketch in the assembly (better yet, a separate component containing only the sketch) with the EJ pin locations. Use this to position the holes in all the plates and inserts. Easy to change, and I've not had nearly the problems.
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Thanks FlowerPot and Ed..:) I dont do many assemblies latley, so it is good to have freindly help.. Beer is on me..
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Damn, I just re-read my post. You'd think english wasn't my native tongue. Not had nearly the problems? Ick.
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I agree with Ed on this. I use this method all the time and really simplifies the top-down assembly approach, especially with really large assemblies that have a lot of inter-part relations. Use a sketch that drives the interactions between parts.
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