Sheet Formats

Dec 04, 2003 5 Replies
K

Newbie from Proe platform trying to make some custom drawing formats with title blocks. Previously in Pro we would have assigned within the parts and assembly files paramaters or variables that contained the part/assembly title, P/N, Originator, dates and etc.



This information would then pass thru into the drawing formats. All I seem to find are notes for having the title blocks obtain info from the properties dialog within the drawing file itself. I would not want to duplicate efforts filling out the part, assembly and drawing variable values increasing errors.


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R

When you ar creating yor templates, put in a "dummy part" drawing view. Then define your parameters using the custom properties from the "dummy part". When you are finished, remove the drawing view and save the template. The custom properties will remain.

Richard

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F

It sounds to me that you might be looking for some of the functionality found in the plugin "custom properties manager", which can be found on

formatting link
. This program lets you import information from the part and automatically insert it into your drawing.

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K

Sorry,

English & Lithuanian is all I can read & write. I would still think this functionality is built within the box set.

part/assembly

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D

You can do this with no add-ons.... There are, although, a few good property input macros available, this one is very cool, I have modified it for our needs and it has saved us much time:

formatting link
When you create your drawing template, edit the sheet format insert a blank note then right click and edit the properties. If you click on the bottom button to the right of this dialog (picture of a link and a hand), the next dialog will allow you to choose some pre-defined links in either the current document (the drawing properties) or in the current model on the sheet. Choose 'Model in view specified in sheet properties' and get a property from the pull down list.

I have these properties (amongst others) on our sheet format: $PRPSHEET:"SW-Folder Name"$PRPSHEET:"SW-File Name".SLDPRT $PRPSHEET:"drw_number" $PRP:"SW-Folder Name"$PRP:"SW-File Name".SLDDRW $PRPSHEET:"vendor" $PRPSHEET:"blank_length" x $PRPSHEET:"blank_width" $PRPSHEET:"thick" MM $PRPSHEET:"material" $PRPSHEET:"parts_blank" $PRPSHEET:"parts_unit" $PRPSHEET:"finish" $PRPSHEET:"weight" g $PRPSHEET:"volume" mm³ $PRPSHEET:"surface" mm² $PRPSHEET:"drawn" $PRPSHEET:"checked" $PRPSHEET:"drw_title" $PRPSHEET:"prog_number"

These all pull the information from the part/assembly model, we have two different templates that we use, one for parts, one for assemblies. You can take and modify these to your needs, just make sure the properties are in the part/assembly model and your drawing sheet will automatically filled out from the model information.

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