I have a part here (recieved from a customer checked out from Windchill) that needs to be checked into another customers Teamcenter PLM system. I do not have any type of access to this Teamcenter system. However, the Teamcenter customer claims that the part cannot be checked into their system without first removing the "Locked" system parameters that Windchill and/or ModelCheck has created.
I have seen in other places (other forums except this one) where this has been a problem, but no solutions have been developed as of yet. I am actively surching the PTC subscription knowledgebase but to no avail.
Has anybody ever found a way to remove these parameters having only access to the part file and Pro/Engineer Wildfire?
If not, anybody know what I can tell the Teamcenter customer (I don't know anthing about Teamcenter) to solve this?
Yeah that was it. I remember doing that on old Pro/E (pre-Wildfire) installations. Now, they move to Wildfire and that doesn't work anymore. Anybody got a solution for Wildfire (1.0+)?
Backup your file to disk. Disconnect from the PDMLink server. Set your config.pro option new_parameters_ui to no. Now try to delete the locked parameters.
I did it with WF2 M160 last year. There may be another hidden option I had set, but I don't think it mattered. Brian Adkins from Deere gave me the information to make it work. With the change in jobs and mail programs, I cannot find the information he sent me.
did you find a way to get rid off those locked parameters? I tried the proposed solution "new_parameter_ui=no", but the locked parameters don't even appear in the menu manager-style menu.
Same problem, cannot submit supplier models into my plm system...
Yes several solutions were concluded after weeks of trial and error to correct the problem. The easiest and best way to delete these locked parameters is to either aquire the Wildfire 2.0 M220 +build OR Wildfire 3.0 M030+ and set the "allow_create_pdm_param=yes" in the config.pro. When this is done (only on these specific builds, this will NOT work for earlier datecodes) the parameters will open unlocked and can be deleted. This procedure has been confirmed both by myself at my company and a fellow collegue of mine at another company. PTC will make this issue known under the TAN#133630. This TAN is not available yet as Wildfire 2.0 M220 and Wildfire 3.0 M030 were very recently released.
The other solution involves the creation of a UDF containing all the part parameters and then importing the UDF into a new blank part without the locked parameters, therefore eliminating the locked parameters. This procedure is extremely messy at first, but once you get the hang of it, its not that bad. This procedure has ONLY been confirmed with part files. Assemblies has NOT been confirmed.
These instructions were successfully performed on Pro/Engineer Wildfire 2.0 M050 and are only verified with part files.
HOST = the Pro/E window containing the original part (with the offending Winchill parameters) TARGET = the new Pro/E window to which the orignal part will be "transfered" (without any parameters) UDF = user defined feature.
1) Open the desired part in the HOST. Make sure to set the working directory as this is where the UDF will be stored.
2) Goto Tools->UDF Library... The UDF Menu Manager should appear.
3) In the menu manager, goto "Create". In the dashboard (bottom message area), a prompt will appear requesting the name of the new UDF. You may call the UDF anything you want, however, I suggest DIFFERENT from the HOST part name, but a name which relates the UDF to the HOST.
e.g. HOST part = test_prt UDF name = udf_test_prt
So in the above example, you would type in "udf_test_part" in the prompt without quotes. It will make it easier to give the UDF a meaningful name (especially with several parts).
4)Type in the UDF name and click the green "Check" button to the right of the prompt. The UDF Menu Manager should expand to Include UDF OPTIONS.
5) Select "Stand Alone" from the UDF OPTIONS. Then click "Done".
6) Another prompt will appear in the dashboard asking if you want to include the reference part. I select "No" here.
7) A new Menu Manager should appear labeled UDF FEATS. The dialog is requesting you to select all of the features that you want to include in the UDF group. On the model tree select the first FEATURE on the list, hold down the SHIFT key, and select the last feature on the list (usually right above the "Insert Here" marker"). This SHOULD select all of the features in the part. Click on the "OK" button in the Select dialog box under the UDF FEATS Menu Manager. Then click "Done". Then click "Done/Return". The UDF FEATS Menu Manager should have disappeared.
8) Click "OK" on the UDF definition dialog box.
9) Click "Done/Return" in the UDF Menu Manager.
10) Create a new part. Name the part whatever you want, however, leave the Common Name field BLANK and uncheck the "Use default template" check box.
11) In the "New File Options" dialog, select the Empty template. Then click the "OK" button.
12) The TARGET window will now appear. This is where the new (without parameters) part will be.
13) Goto Insert->User-Defined Feature... An "Open" dialog will appear, select the UDF group that you created in the HOST window. (In my case, udf_test_prt.gph).
14) A PLACE OPTS Menu Manager will appear. Select "Independent", then select "Done".
15) A SCALE Menu Manager will appear. Assuming that both the HOST and TARGET window are in the same dimension setup. Select "Same Dims" and then select "Done".
16) A DISP OPTION Menu Manager will appear. Select "Normal" and then select "Done".
17) Select the "OK" button in the "Group Elements" definition dialog.
18) A GRP PLACE Menu Manager will appear. Select "Done" to finish the UDF import operation.
19) The features that you made into a UDF group in the HOST window will now appear as a feature group in the Model Tree of the TARGET window. To correct this, simply select the feature group in the TARGET window Model Tree (in my case feature "Group UDF_TEST_PRT"), right click, and select "Ungroup" from the drop-down list.
20) Open the Tools->Parameters... window. Sometimes PTC_COMMON_NAME will be in there. However, it is not locked. Simply delete it. Now, no parameter will exist.
--End of Instructions--
I hope this helps. I thought I would post this here jsut in case anybody requires an immediate solution for part files.
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