I have only recently begun dealing with weldments and cut lists.
On the part I am working on, it seems that SW2006 is NOT (apparently)
correctly grouping similar/identical weldment items in my Cut List.
ie. The Cut List on the part/drawing indicates that there are more
unique weldments than what I know there should be.
What criteria does SW check in order to detemine if two weldements
should listed as belonging to the same Cut List Item folder?
How can I correct/work around this situation?
First try right mouse clicking on the cut list icon in the feature tree
making sure automatic is checked and then try update. If this doesn't
work you my have to delete the cut list and recreate it. Also you my
want to check what SP your running we had some problems with this in
ealier SP in 06.
Copied this from a answer I gave to a similar post last year (Google
You can click and drag the "Structural Member" out of the "Cut List
Item" folder drag it to the "Cut List" then right click it and "Create
Cut List Item"
It also sometimes doesn't recognise the fact that two items are
identical, in which case you can drag the "Structural Member" from one
"Cut List Item" folder to another.
Also, be aware that a weldment item that is the mirror of another will
incorrectly be identifed as identical. I ran into this last year a few
times, actually ended up with a bit of scrap aluminum! Although it's
possible they fixed that problem.
Thanks for the tips.
Deleting and recreating the cut list did not fix the problem.
The SW installation in 2006 SP0 but when the part is opened and a new
cut list generated on a PC with the latest SP it still incorrectly
separates the two identical weldements int the list.
As suggested, I can drag and drop the elements into whatever Cut List
Item folder you like, essentially overwitring whatever SW thinks. If
you do this I see that the cut list table in your drawing updates
automatically to refelct these changes but any balloon callouts do not.
In fact, I have noticed that once the initial ballon callouts have
been assigned, any further changes to anything in the cut list (changed
order, regroupings etc) ARE NOT reflected at all in the call outs.
It seems that once the balloon call out it placed in a drawing, it
essentially immediately becomes "orphaned".
I have found that ANY changes to the cutlist in either part or the
drawing cutlist table will not be refected in the balloon callouts.
Is this how it is or have I missed something? It is extremely tedious
and annoying on a part with 30+ weldments having to delete then
recreate and reposition new ones because you want to modify in some way
the cut list grouping/order etc.
Also, where is the information that holds the weldment "Description" in
a part as seen in the drawing cut list table stored/kept or when you
right click the Cut List Item folder and select Properties? I have one
weldment I am using that keeps on showing the wrong "Description" in
the cut list. I want to cpermanently edut it but I haven't been able
to do it. I can edit the Description field in the part by editing the
Cut List Item properties, and the change gets refelcted in the drawing
cut list table, but if I delete the cut list from the part and recreate
the cut list, the same incorrect description keeps popping up when it
is recreated. Where is this information being held?
This whole weldments thing seems kind broken :(
balloons update in SolidWorks 2005 SP5, (I think) I'll test again tomorrow.
These custom properties, as you have discovered, can be overwritten in
the weldment. However the default properties are stored in the weldment
profile. If you want a different default description you need to make a
custom profile and alter the properties within that custom profile.
Details on making a custom profile can be found in the help file.
Just wait till you make an edrawing of one, you'll pull your hair out.
To get the edrawing to work you can't have shaded views on, or a least
you can't in 2005.