I am not understanding the file set up and the "save as" in SW. I have an existing assembly that I want to create a copy of but I don't want the new assembly to reference the original. In the new Assembly I want to delete some of the components that I don't want. How do I create this new assembly and take all the existing parts and copy them to a new folder. I want all the references deleted so that I can edit a part and it won't change the original.
"Nathan Feculak" wrote in news:guO0c.40797$A12.9330@edtnps84:
One possible method that I use...I'm sure there are others.
Open original assembly
Save As...
In save as dialog, click References
In References dialog, click Select All
In References dialog, click browse and select new folder for new assembly
In References dialog, click ok
In Save As dialog, click Save
Done
MHill
If you truly want a divorced copy, open the main assy, do a Find References and copy all files from there to a location. At that point you will have a complete copy of everything that is not related to anything. Make all your changes there.
If you actually want the new assy to reference some of the same part files, then just open the main assy, do a File/SaveAs and check the Save as copy box. Then go open the new, copied assy file that still references the same part files.
WT
A third alternative is to use SW Explorer which can also add a prefix or suffix to the new files to keep them from getting confused with the old files. Having a bunch of files named the same thing on your hard drive is not a great idea.
matt
"Nathan Feculak" wrote in news:guO0c.40797$A12.9330@edtnps84:
"Nathan Feculak" wrote in news:guO0c.40797$A12.9330@edtnps84:
Three ways to 'divorce' and copy SW assemblies are:
1: File | Find References : Choose not to preserve directory structure and select a new directory. Everything required (but not drawings) will be copied.2: File | Saveas then check the references button - select all - browse to a new directory then click ok, then check 'copy' and again browse to the new directory. Everything required (but not drawings) will be copied.
3: Solidworks Explorer: This is the most thorough way. Using solidworks explorer you can copy all parts and drawings to a new folder, updating references along the way.Hope this helps some! Anyhow - what you sent worked fine although I found some external references looking for parts that don't exist anymore? But not anything that caused trouble
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