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How do I roll-back a revision using SW revision tables?

I added to many revisions to a revison table. How can I rollback a revision? When I remove a row, it doesnt reset the revision number back.

EX. I have a revision table with 3 revisions. I added a 4th row for rev 4, but decide I dont want rev 4. I can manually change my Revision custom property to 3, but the next time I add a revision to the table it comes up as Rev 5.

Any ideas? Seems like theres gotta be a simple answer to this, but I cant find one :P

Reply to
SW Monkey
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I didn't realize how annoying this limitation is until you mentioned it here. :) I'd like to know the answer to, or maybe sumfin that requires an enhancement request.

Matt

Reply to
fcsuper

fcsuper,

Sorry, not a simple answer. Currently, the only way I have found to do this is to recreate it. But its a little more involved than simply deleting and replacing. Here is what you have to do:

  1. Print the drawing as it is. You will have to refer to it when recreating your Revision table and Revision balloons.
  2. Delete the Revision table. It will ask you if you want to delete the balloons. If you want them to remain linked after recreating it, you will have to recreate the balloons as well. With that being said, you decide if you want to delete the balloons.
  3. Delete the Revision custom property. Not just the value. You must delete the whole row.
  4. Save and close the drawing.
  5. Open the drawing and recreate the table/balloons, referencing the drawing that you printed.

If you skip steps 3 & 4, you will end up with the same problem of not resetting itself.

It sucks, but this is the only solution I have found.

Reply to
Seth Renigar

Its things like this that I dont understand how it gets past SolidWorks QA dept. You shouldnt have to go through such BS.

Anyone know if they fixed this in 2006 or 2007 ? Im still using 2005.

Reply to
SW Monkey

Quick work-a-round

  1. delete last rev
  2. go to tools>options> Document properties tab tables > under revision table > Alpha/Numerical control, select the one NOT selected. select ok (closed documents property)
  3. repeat step 2.

ambush

Reply to
ambush

Coool! Haven't tried that yet....

Reply to
Seth Renigar

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