extracting 2d geom in Pro Detail

Scott,
Pro/DETAIL has the functionality that you're looking for. It's called 'Snapshot'. You can choose individual views to 'Snapshot' or 'All Views' to convert all of the 2-D drawing's views to non-associative, 2-D, draft entities. It works really well, but there are a few things that you should probably be aware of:
1) Cross-section cutting plane lines and their corresponding arrowheads will get their appearances changed. Not for the good, by the way.
2) You can create new dimensions that reference the remaining 2-D draft entities. Their values will be based upon a 1:1 'Draft Scale'. *NOTE: There is a drawing setup file option called 'draft_scale' that can be modified to reflect the scale that you would like for any new dimensions' values to be based upon. Also, with Pro/LEGACY activated while working in a drawing that has had all of its views snapshotted, you will be able to assign individual view scales to any view that you would like. The Pro/LEGACY module allows the user to work in the same manner in which they would with other strictly 2-D CAD applications. The functionality may not be as powerful as traditional 2-D systems such as AutoCAD, Microstation, CADRA, CADAM, etc., but it will suffice. I can assure you of it. I've tested Pro/LEGACY and Pro/DETAIL out very thoroughly and it works just fine once you understand its behaviors.
To get view geometry *minus* dimensions over to another 2-D drawing, you'll have to create a Symbol of it in the source drawing. Then place it as a Symbol instance in the target drawing. And you'll have to 'Explode' the Symbol in the target drawing in order to be able to work with it. You will need to re-dimension this geometry in the target drawing. That is the one limitation that is rather significant for most users. Other than this limitation, the combination of Pro/DETAIL and Pro/LEGACY is functional for non-associative, 2-D CAD work. Of course the menu structure is a bit dissheveled, but that's the nature of most things PTC. :-)
S.T.

: Scott, : : Pro/DETAIL has the functionality that you're looking for. It's called : 'Snapshot'.
'Edit>Draft entities'

Some additional info for you Scott. Release 2001's Snapshot functionality can be found under: Views-Modify View-Snapshot-Pick View/All Views
In Pro/E Wildfire, as David Janes pointed out already, the Snapshot functionality can be accessed under: Edit-Convert to Draft Entities
With Wildfire, you pre-select the view(s) and then choose Edit-Convert to Draft Entities to Snapshot them; which converts the associative view geometry to non-associative draft entities.
Best regards,
S.T.