80-20 aluminum extrusion dwg import

Damn those DWG's... ;-) The outer contour of the profile is not closed. Use the Contour Select tool to find out where the contour is open (upper & lower right corners). Zoom to the open gaps, select the endpoints and add 'Merge Points' relation. Selection filter may be needed since the extreme zooming can make it hard to hit the endpoints.

Hope this helps!

-h-

No registeration was needed at all to download DWG's.

-h-

Troy,

The drawings that they give you on 80/20 are junk,if you look close lines don't even connect. I have built part of quite a few

later

Andrew Grove

actually it is closed. i check in acad and it imports into inventor just fine as is. it must be a problem with how solid works imports acad files.

check for youself if you have autocad. its a closed pline just like he said.

Matt

ok. found the problem.

the dwg has 2 arcs with very small dimensions right where solidworks looses it.

the radius is 0.00000213

the solid works importer just ignores those arc so you end up with a gap.

i would erase them and re-close it in acad and bring it back into sw.

Matt

Couple options.

You could import the dwg then close the sketch. Start a new sketch and use the dwg as a reference. Convert entities, make lines collinear and make sure all the end point connect. Depending on the profile this could be time consuming.

Another option I have found that works well is to open the dwg in AutoCAD. Explode everything and then convert all lines to polylines. Save the dwg and then import that into SolidWorks. If that doesen't close all the points it usually gets about 90%.