Dimensional Help Please - Foreshortened Radius

Hi Folks.
Here is my situation. I have a very large radius which I am
dimensioning in a drawing, the center of which is off the drawing.
I can effectively alter the large radius dimension using properies and
foreshorten it. This all works as planned.
But, I see no way to bind the dimensions for the center of the radius
to the center once the radius dimension is foreshrtened. The dims for
the centerline are still off the page.
Any ideas?
Thanks,
SMA
Reply to
Sean-Michael Adams
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Not sure if this is exactly what you want as I may be miss understanding you however maybe this will give you a good idea as to where to go from where you are at..
only way I have found to do this is:
1 create the dimension as normal (or import model item dimension)
Reply to
RENDERMAN
just thinking outloud, break view
Reply to
kenneth b
RMB on radius dimension Select Properties Check the box next to Foreshortened Radius (see SW help also)
Kman
Reply to
Kman
guess not
you could use a note (link to dims) and specify the center as x,y coordinates. we are talking about the linear placement of the center, are we not?
Reply to
kenneth b
With large 'off the page' dimensions try the following (I use it all the time when dimensioning detail views):
RMB on dim and select properties. Select 'Display' button on dialogue box, De-select one of the extension and dimension lines (i.e. either the first or the second - it will depend which section of the drawing view is still visible), and de-select the centre dimension between extension lines. OK this (twice for the 2 dialogue boxes). You will now find that you have a shortened dimension that you can drag around to get the length required.
HTH
Merry :-)
Reply to
Merry Owen
But what if you want to the center point? I ask SolidWorks for a solution to this a long time ago.
Reply to
SWuser
OK what I'm about to suggest isn't binding but pictorially it gets the job done. I almost hate to say this because I used to rag on people who would fake dimensions in AutoCAD.
Create the foreshortened radius dimension Place a sketch point that appears to be on the end of foreshortened dimension line Dimension from this sketch point to wherever Type over the in properties with the value desired
Merry's suggestion is best and would also add a note next to the dimension "to center of radius" or something like that.
Kman
Reply to
Kman
Merry,
Nice elegant solution. I like this one. It's a bit "hokey" that we have to do it this way but it will work and does not look to bad when all is said and done.
Thanks again-
SMA
And thanks to all who gave me a boost - (Steve, Kenneth, Kman, Merry)
Reply to
Sean-Michael Adams

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